kicad/pcbnew/gpcb_exchange.cpp

/**********************************************************************/
/* Import functions to import footprints from a gpcb (Newlib) library */
/**********************************************************************/

#include "fctsys.h"

#include "wxstruct.h"
#include "common.h"
#include "pcbnew.h"
#include "trigo.h"


/* read parameters from a line, and return all params in a wxArrayString
 * each param is in one wxString, and double quotes removed if exists
 */
static void Extract_Parameters( wxArrayString& param_list, char* text );
static bool TestFlags( const wxString& flg_string, long flg_mask, const wxChar* flg_name );


/**************************************************************/
bool MODULE::Read_GPCB_Descr( const wxString& CmpFullFileName )
/**************************************************************/

/**
 * Function Read_GPCB_Descr
 * Read a footprint description in GPCB (Newlib) format
 * @param CmpFullFileName = Full file name (there is one footprint per file.
 * this is also the footprint name
 * @return bool - true if success reading else false.
 */

/* a sample is
 *
 * Element["" "" "" "" 29000 44000 0 0 0 100 ""]
 * (
 * Pad[-5000 0 -4000 0 4999 0 4999 "" "1" "square"]
 * Pad[4000 0 5000 0 4999 0 4999 "" "2" "square,edge2"]
 * ElementLine [8000 3000 1000 3000 199]
 * ElementLine [8000 -3000 8000 3000 199]
 * ElementLine [-8000 3000 -1000 3000 199]
 * ElementLine [-8000 -3000 -1000 -3000 199]
 * ElementLine [8000 -3000 1000 -3000 199]
 * ElementLine [-8000 -3000 -8000 3000 199]
 * )
 *
 * Format
 * Element [SFlags "Desc" "Name" "Value" MX MY TX TY TDir TScale TSFlags]
 * Element (NFlags "Desc" "Name" "Value" MX MY TX TY TDir TScale TNFlags)
 * Element (NFlags "Desc" "Name" "Value" TX TY TDir TScale TNFlags)
 * Element (NFlags "Desc" "Name" TX TY TDir TScale TNFlags)
 * Element ("Desc" "Name" TX TY TDir TScale TNFlags)
 * (
 * . . . contents . . . *
 * )
 * With:
 * SFlags Symbolic or numeric flags, for the element as a whole.
 * NFlags Numeric flags, for the element as a whole.
 * Desc The description of the element. This is one of the three strings which can be
 * displayed on the screen.
 * Name The name of the element, usually the reference designator.
 * Value The value of the element.
 * MX MY The location of the element<EFBFBD>s mark. This is the reference point for placing the element and its pins and pads.
 * TX TY The upper left corner of the text (one of the three strings).
 * TDir The relative direction of the text. 0 means left to right for an unrotated element, 1 means up, 2 left, 3 down.
 * TScale Size of the text, as a percentage of the <EFBFBD>default<EFBFBD> size of of the font (the default font is about 40 mils high). Default is 100 (40 mils).
 * TSFlags Symbolic or numeric flags, for the text.
 * TNFlags Numeric flags, for the text.
 *
 * Elements may contain pins, pads, element
 *
 * ElementLine [X1 Y1 X2 Y2 Thickness]
 * ElementLine (X1 Y1 X2 Y2 Thickness)
 *
 * ElementArc [X Y Width Height StartAngle DeltaAngle Thickness]
 * ElementArc (X Y Width Height StartAngle DeltaAngle Thickness)
 *   (rotation in clockwise)
 * Pad [rX1 rY1 rX2 rY2 Thickness Clearance Mask "Name" "Number" SFlags]
 * Pad (rX1 rY1 rX2 rY2 Thickness Clearance Mask "Name" "Number" NFlags)
 * Pad (aX1 aY1 aX2 aY2 Thickness "Name" "Number" NFlags)
 * Pad (aX1 aY1 aX2 aY2 Thickness "Name" NFlags)
 *
 * Pin [rX rY Thickness Clearance Mask Drill "Name" "Number" SFlags]
 * Pin (rX rY Thickness Clearance Mask Drill "Name" "Number" NFlags)
 * Pin (aX aY Thickness Drill "Name" "Number" NFlags)
 * Pin (aX aY Thickness Drill "Name" NFlags)
 * Pin (aX aY Thickness "Name" NFlags)
 *
 * Object Flags :
 *
 * Note that object flags can be given numerically (like 0x0147) or symbolically (like
 * "found,showname,square". Some numeric values are reused for different object types.
 * The table below lists the numeric value followed by the symbolic name.
 * 0x0001 pin
 * If set, this object is a pin. This flag is for internal use only.
 * 0x0002 via
 * Likewise, for vias.
 * 0x0004 found
 * If set, this object has been found by FindConnection().
 * 0x0008 hole
 * For pins and vias, this flag means that the pin or via is a hole without a copper
 * annulus.
 * 0x0010 rat
 * If set for a line, indicates that this line is a rat line instead of a copper trace.
 * 0x0010 pininpoly
 * For pins and pads, this flag is used internally to indicate that the pin or pad
 * overlaps a polygon on some layer.
 * 0x0010 clearpoly
 * For polygons, this flag means that pins and vias will normally clear these polygons
 * (thus, thermals are required for electrical connection). When clear, polygons
 * will solidly connect to pins and vias.
 * 0x0010 hidename
 * For elements, when set the name of the element is hidden.
 * 0x0020 showname
 * For elements, when set the names of pins are shown.
 * 0x0020 clearline
 * For lines and arcs, the line/arc will clear polygons instead of connecting to
 * them.
 * 0x0020 fullpoly
 * For polygons, the full polygon is drawn (i.e. all parts instead of only the biggest
 * one).
 * 0x0040 selected
 * Set when the object is selected.
 * 0x0080 onsolder
 * For elements and pads, indicates that they are on the solder side
 * 0x0080 auto
 * For lines and vias, indicates that these were created by the autorouter.
 * 0x0100 square
 * For pins and pads, indicates a square (vs round) pin/pad.
 * 0x0200 rubberend
 * For lines, used internally for rubber band moves.
 * 0x0200 warn
 * For pins, vias, and pads, set to indicate a warning.
 * 0x0400 usetherm
 * Obsolete, indicates that pins/vias should be drawn with thermal fingers.
 * 0x0400 Obsolete, old files used this to indicate lines drawn on silk.
 * 0x0800 octagon
 * Draw pins and vias as octagons.
 * 0x1000 drc
 * Set for objects that fail DRC.
 * 0x2000 lock
 * Set for locked objects.
 * 0x4000 edge2
 * For pads, indicates that the second point is closer to the edge. For pins, indicates
 * that the pin is closer to a horizontal edge and thus pinout text should be vertical.
 * 0x8000 marker
 * Marker used internally to avoid revisiting an object.
 * 0x10000 nopaste
 * For pads, set to prevent a solderpaste stencil opening for the pad. Primarily
 * used for pads used as fiducials.
 */
{
    #define TEXT_DEFAULT_SIZE  400
    #define OLD_GPCB_UNIT_CONV 10
    #define NEW_GPCB_UNIT_CONV 0.1
    FILE*         cmpfile;
    double        conv_unit = NEW_GPCB_UNIT_CONV; // GPCB unit = 0.01 mils and pcbnew 0.1
    // Old version unit = 1 mil, so conv_unit is 10 or 0.1
    bool          success = true;
    char          Line[1024];
    int           NbLine = 0;
    long          ibuf[100];
    EDGE_MODULE*  DrawSegm, * LastModStruct = NULL;
    D_PAD*        LastPad = NULL, * Pad;
    wxArrayString params;
    int           iprmcnt, icnt_max, iflgidx;

    if( ( cmpfile = wxFopen( CmpFullFileName, wxT( "rt" ) ) ) == NULL )
        return false;

    GetLine( cmpfile, Line, &NbLine );

    params.Clear();
    Extract_Parameters( params, Line );

    iprmcnt  = 0;
    icnt_max = params.GetCount();

    if( params[iprmcnt].CmpNoCase( wxT( "Element" ) ) != 0 )
    {
        fclose( cmpfile );
        return false;
    }

    // Test symbol after "Element": if [ units = 0.01 mils, and if ( units = 1 mil
    iprmcnt++;
    if( params[iprmcnt] == wxT( "(" ) )
        conv_unit = OLD_GPCB_UNIT_CONV;

    /* Analyse first line :
     * Element [element_flags, description, pcb-name, value, mark_x, mark_y, text_x, text_y,
     *		text_direction, text_scale, text_flags]
     */

    // Read flags (unused)
    iprmcnt++;

    // Read description
    iprmcnt++;
    m_Doc = params[iprmcnt];

    // Read pcb-name (reference )
    iprmcnt++;
    m_Reference->m_Text = params[iprmcnt];

    // Read value
    iprmcnt++;
    m_Value->m_Text = params[iprmcnt];

    // Read other infos
    iprmcnt++;
    for( int ii = 0; ii < 6; ii++ )
    {
        if( iprmcnt < icnt_max )
        {
            success  = false;
            ibuf[ii] = 0;
        }
        else
            params[iprmcnt].ToLong( &ibuf[ii] );
        iprmcnt++;
    }

    m_Reference->m_Pos.x  = (int) round( ibuf[2] * conv_unit );
    m_Reference->m_Pos.y  = (int) round( ibuf[3] * conv_unit );;
    m_Reference->m_Orient = ibuf[4] * 900;

    // Calculate size: default is 40 mils (400 pcb units)
    // real size is:  default * ibuf[5] / 100 (size in gpcb is given in percent of defalut size
    ibuf[5] *= TEXT_DEFAULT_SIZE; ibuf[5] /= 100;
    m_Reference->m_Size.x = m_Reference->m_Size.y = MAX( 20, ibuf[5] );
    m_Reference->m_Width  = m_Reference->m_Size.x / 10;
    m_Value->m_Orient = m_Reference->m_Orient;
    m_Value->m_Size   = m_Reference->m_Size;
    m_Value->m_Width  = m_Reference->m_Width;

    while( GetLine( cmpfile, Line, &NbLine, sizeof(Line) - 1 ) != NULL )
    {
        params.Clear();
        Extract_Parameters( params, Line );
        if( params.GetCount() > 3 )    // Test units value for a string line param (more than 3 params : ident [ xx ] )
        {
            if( params[1] == wxT( "(" ) )
                conv_unit = OLD_GPCB_UNIT_CONV;
            else
                conv_unit = NEW_GPCB_UNIT_CONV;
        }

        if( params[0].CmpNoCase( wxT( "ElementLine" ) ) == 0 )      // line descr
        {                                                           // Format: ElementLine [X1 Y1 X2 Y2 Thickness]
            DrawSegm = new EDGE_MODULE( this );
            DrawSegm->SetLayer( SILKSCREEN_N_CMP );
            DrawSegm->m_Shape = S_SEGMENT;

            if( LastModStruct == NULL )
            {
                DrawSegm->Pback = this;
                m_Drawings = DrawSegm;
            }
            else
            {
                DrawSegm->Pback      = LastModStruct;
                LastModStruct->Pnext = DrawSegm;
            }
            int* list[5] = {
                &DrawSegm->m_Start0.x, &DrawSegm->m_Start0.y,
                &DrawSegm->m_End0.x,   &DrawSegm->m_End0.y,
                &DrawSegm->m_Width
            };
            for( unsigned ii = 0; ii < 5; ii++ )
            {
                long dim;
                if( ii < (params.GetCount() - 2) )
                {
                    if( params[ii + 2].ToLong( &dim ) )
                        *list[ii] = (int) round( dim * conv_unit );
                }
            }

            DrawSegm->SetDrawCoord();
            LastModStruct = DrawSegm;
            continue;
        }

        if( params[0].CmpNoCase( wxT( "ElementArc" ) ) == 0 )       // Arc descr
        {                                                           // format: ElementArc [X Y Width Height StartAngle DeltaAngle Thickness]
            // pcbnew does know ellipse so we must have Width = Height
            DrawSegm = new EDGE_MODULE( this );
            DrawSegm->SetLayer( SILKSCREEN_N_CMP );
            DrawSegm->m_Shape = S_ARC;

            if( LastModStruct == NULL )
            {
                DrawSegm->Pback = this;
                m_Drawings = DrawSegm;
            }
            else
            {
                DrawSegm->Pback      = LastModStruct;
                LastModStruct->Pnext = DrawSegm;
            }
            for( unsigned ii = 0; ii < 7; ii++ )
            {
                long dim;
                if( ii < (params.GetCount() - 2) )
                {
                    if( params[ii + 2].ToLong( &dim ) )
                        ibuf[ii] = dim;
                    else
                        ibuf[ii] = 0;
                }
                else
                    ibuf[ii] = 0;
            }

            int     rayon = (ibuf[2] + ibuf[3]) / 4; // for and arc: ibuf[3] = ibuf[4]. pcbnew does not know ellipses
            wxPoint centre;
            centre.x = (int) round( ibuf[0] * conv_unit );
            centre.y = (int) round( ibuf[1] * conv_unit );
            DrawSegm->m_Start0 = centre;
            int start_angle = ibuf[4] * 10;     // Pcbnew uses 0.1 degrees as units
            start_angle       -= 1800;          // Use normal X axis  as reference
            DrawSegm->m_Angle  = ibuf[5] * 10;  // Angle value is clockwise in gpcb and pcbnew
            DrawSegm->m_End0.x = (int) round( rayon * conv_unit );
            DrawSegm->m_End0.y = 0;
            RotatePoint( &DrawSegm->m_End0, -start_angle );	// Calculate start point coordinate of arc
            DrawSegm->m_End0 += centre;

            DrawSegm->m_Width = (int) round( ibuf[6] * conv_unit );
            DrawSegm->SetDrawCoord();
            LastModStruct = DrawSegm;
            continue;
        }

        if( params[0].CmpNoCase( wxT( "Pad" ) ) == 0 )      // Pad with no hole (smd pad)
        {                                                   //	format: Pad [x1 y1 x2 y2 thickness clearance mask "name" "pad_number" flags]
            Pad = new D_PAD( this );
            Pad->m_PadShape     = PAD_RECT;
            Pad->m_Masque_Layer = CMP_LAYER | SOLDERMASK_LAYER_CMP | SOLDERPASTE_LAYER_CMP;

            // Set shape from flags
            iflgidx = params.GetCount() - 2;
            if( TestFlags( params[iflgidx], 0x0080, wxT( "onsolder" ) ) )
                Pad->m_Masque_Layer = CUIVRE_LAYER | SOLDERMASK_LAYER_CU | SOLDERPASTE_LAYER_CU;

            for( unsigned ii = 0; ii < 5; ii++ )
            {
                if( ii < params.GetCount() - 2 )
                {
                    long dim;
                    if( params[ii + 2].ToLong( &dim ) )
                        ibuf[ii] = (int) round( dim * conv_unit );
                }
                else
                    ibuf[ii] = 0;
            }

            // Read name:
            // Currently unused

            // Read pad number:
            if( params.GetCount() > 10 )
            {
                strncpy( Pad->m_Padname, CONV_TO_UTF8( params[10] ), 4 );
            }
            Pad->m_Pos.x  = (ibuf[0] + ibuf[2]) / 2;
            Pad->m_Pos.y  = (ibuf[1] + ibuf[3]) / 2;
            Pad->m_Size.x = ibuf[4] + abs( ibuf[0] - ibuf[2] );
            Pad->m_Size.y = ibuf[4] + abs( ibuf[1] - ibuf[3] );
            Pad->m_Pos.x += m_Pos.x;
            Pad->m_Pos.y += m_Pos.y;
            if( !TestFlags( params[iflgidx], 0x0100, wxT( "square" ) ) )
            {
                if( Pad->m_Size.x == Pad->m_Size.y )
                    Pad->m_PadShape = PAD_ROUND;
                else
                    Pad->m_PadShape = PAD_OVAL;
            }


            if( LastPad == NULL )
            {
                Pad->Pback = (EDA_BaseStruct*) this;
                m_Pads = Pad;
            }
            else
            {
                Pad->Pback     = (EDA_BaseStruct*) LastPad;
                LastPad->Pnext = (EDA_BaseStruct*) Pad;
            }
            LastPad = Pad;
            continue;
        }

        if( params[0].CmpNoCase( wxT( "Pin" ) ) == 0 )      // Pad with hole (trough pad)
        {                                                   // format: Pin[x y Thickness Clearance Mask DrillHole Name Number Flags]
            Pad = new D_PAD( this );
            Pad->m_PadShape     = PAD_ROUND;
            Pad->m_Masque_Layer = ALL_CU_LAYERS |
                                  SILKSCREEN_LAYER_CMP |
                                  SOLDERMASK_LAYER_CMP |
                                  SOLDERMASK_LAYER_CU;
            iflgidx = params.GetCount() - 2;
            if( TestFlags( params[iflgidx], 0x0100, wxT( "square" ) ) )
                Pad->m_PadShape = PAD_RECT;
            for( unsigned ii = 0; ii < 6; ii++ )
            {
                if( ii < params.GetCount() - 2 )
                {
                    long dim;
                    if( params[ii + 2].ToLong( &dim ) )
                        ibuf[ii] = (int) round( dim * conv_unit );
                }
                else
                    ibuf[ii] = 0;
            }

            // Read name:
            // Currently unused

            // Read pad number:
            if( params.GetCount() > 9 )
            {
                strncpy( Pad->m_Padname, CONV_TO_UTF8( params[9] ), 4 );
            }
            Pad->m_Pos.x   = ibuf[0];
            Pad->m_Pos.y   = ibuf[1];
            Pad->m_Drill.x = Pad->m_Drill.y = ibuf[5];
            Pad->m_Size.x  = Pad->m_Size.y = ibuf[3] + Pad->m_Drill.x;
            Pad->m_Pos.x  += m_Pos.x;
            Pad->m_Pos.y  += m_Pos.y;
            if( (Pad->m_PadShape == PAD_ROUND) && (Pad->m_Size.x != Pad->m_Size.y) )
                Pad->m_PadShape = PAD_OVAL;

            if( LastPad == NULL )
            {
                Pad->Pback = (EDA_BaseStruct*) this;
                m_Pads = Pad;
            }
            else
            {
                Pad->Pback     = (EDA_BaseStruct*) LastPad;
                LastPad->Pnext = (EDA_BaseStruct*) Pad;
            }
            LastPad = Pad;
            continue;
        }
    }

    fclose( cmpfile );

    if( m_Value->m_Text.IsEmpty() )
        m_Value->m_Text = wxT( "Val**" );
    if( m_Reference->m_Text.IsEmpty() )
    {
        wxFileName filename( CmpFullFileName );
        m_Reference->m_Text = filename.GetName();
    }

    /* Recalculate the bounding box */
    Set_Rectangle_Encadrement();
    return success;
}


/***********************************************************************/
static void Extract_Parameters( wxArrayString& param_list, char* text )
/***********************************************************************/

/* Read a text line and extract params and tokens.
 * special chars are:
 * [ ] ( )	Begin and end of parameter list and units indicator
 * " is a string delimiter
 * space is the param separator
 * The first word is the keyword
 * the second item is one of ( ot [
 * other are parameters (number or delimited string)
 * last parameter is ) or ]
 */
{
    int      key;
    wxString tmp;

    while( *text != 0 )
    {
        key = *text;
        text++;

        switch( key )
        {
        case '[':
        case ']':
        case '(':
        case ')':
            if( !tmp.IsEmpty() )
            {
                param_list.Add( tmp );
                tmp.Clear();
            }
            tmp.Append( key );
            param_list.Add( tmp );
            tmp.Clear();
            break;

        case '\n':
        case '\r':
        case '\t':
        case ' ':
            if( !tmp.IsEmpty() )
            {
                param_list.Add( tmp );
                tmp.Clear();
            }
            break;

        case '"':
            while( *text != 0 )
            {
                key = *text;
                text++;
                if( key == '"' )
                {
                    param_list.Add( tmp );
                    tmp.Clear();
                    break;
                }
                else
                    tmp.Append( key );
            }

            break;

        default:
            tmp.Append( key );
            break;
        }
    }
}


/***********************************************************************************/
bool TestFlags( const wxString& flg_string, long flg_mask, const wxChar* flg_name )
/***********************************************************************************/

/** Function TestFlags
 * Test flag flg_mask or flg_name.
 * @param flg_string = flsg list to test: can be a bit field flag or a list name flsg
 * a bit field flag is an hexadecimal value: Ox00020000
 * a list name flsg is a string list of flags, comma separated like square,option1
 * @param flg_mask = flsg list to test
 * @param flg_mask = flsg list to test
 * @return true if found
 */
{
    wxString strnumber;

    if( flg_string.StartsWith( wxT( "0x" ),
           &strnumber ) || flg_string.StartsWith( wxT( "0X" ), &strnumber ) )
    {
        long lflags;
        if( strnumber.ToLong( &lflags, 16 ) )
            if( lflags & flg_mask )
                return true;
    }
    else if( flg_string.Contains( flg_name ) )
        return true;

    return false;
}