121 lines
3.6 KiB
Python
121 lines
3.6 KiB
Python
'''
|
|
A python script example to create various plot files from a board:
|
|
Fab files
|
|
Doc files
|
|
Gerber files
|
|
|
|
Important note:
|
|
this python script does not plot frame references.
|
|
the reason is it is not yet possible from a python script because plotting
|
|
plot frame references needs loading the corresponding page layout file
|
|
(.wks file) or the default template.
|
|
|
|
This info (the page layout template) is not stored in the board, and therefore
|
|
not available.
|
|
|
|
Do not try to change SetPlotFrameRef(False) to SetPlotFrameRef(true)
|
|
the result is the pcbnew lib will crash if you try to plot
|
|
the unknown frame references template.
|
|
'''
|
|
|
|
import sys
|
|
|
|
from pcbnew import *
|
|
filename=sys.argv[1]
|
|
|
|
board = LoadBoard(filename)
|
|
|
|
pctl = PLOT_CONTROLLER(board)
|
|
|
|
popt = pctl.GetPlotOptions()
|
|
|
|
popt.SetOutputDirectory("plot/")
|
|
|
|
# Set some important plot options:
|
|
popt.SetPlotFrameRef(False)
|
|
popt.SetLineWidth(FromMM(0.35))
|
|
|
|
popt.SetAutoScale(False)
|
|
popt.SetScale(1)
|
|
popt.SetMirror(False)
|
|
popt.SetUseGerberAttributes(True)
|
|
popt.SetExcludeEdgeLayer(False);
|
|
popt.SetScale(1)
|
|
popt.SetUseAuxOrigin(True)
|
|
|
|
# This by gerbers only (also the name is truly horrid!)
|
|
popt.SetSubtractMaskFromSilk(False) #remove solder mask from silk to be sure there is no silk on pads
|
|
|
|
#Create a pdf file of the top silk layer
|
|
pctl.SetLayer(F_SilkS)
|
|
pctl.OpenPlotfile("Silk", PLOT_FORMAT_PDF, "Assembly guide")
|
|
pctl.PlotLayer()
|
|
|
|
|
|
# Once the defaults are set it become pretty easy...
|
|
# I have a Turing-complete programming language here: I'll use it...
|
|
# param 0 is a string added to the file base name to identify the drawing
|
|
# param 1 is the layer ID
|
|
plot_plan = [
|
|
( "CuTop", F_Cu, "Top layer" ),
|
|
( "CuBottom", B_Cu, "Bottom layer" ),
|
|
( "PasteBottom", B_Paste, "Paste Bottom" ),
|
|
( "PasteTop", F_Paste, "Paste top" ),
|
|
( "SilkTop", F_SilkS, "Silk top" ),
|
|
( "SilkBottom", B_SilkS, "Silk top" ),
|
|
( "MaskBottom", B_Mask, "Mask bottom" ),
|
|
( "MaskTop", F_Mask, "Mask top" ),
|
|
( "EdgeCuts", Edge_Cuts, "Edges" ),
|
|
]
|
|
|
|
|
|
for layer_info in plot_plan:
|
|
pctl.SetLayer(layer_info[1])
|
|
pctl.OpenPlotfile(layer_info[0], PLOT_FORMAT_GERBER, layer_info[2])
|
|
print layer_info[0]
|
|
pctl.PlotLayer()
|
|
|
|
# Our fabricators want two additional gerbers:
|
|
# An assembly with no silk trim and all and only the references
|
|
# (you'll see that even holes have designators, obviously)
|
|
popt.SetPlotReference(True)
|
|
popt.SetPlotValue(False)
|
|
popt.SetPlotInvisibleText(False)
|
|
|
|
pctl.SetLayer(F_SilkS)
|
|
pctl.OpenPlotfile("AssyTop", PLOT_FORMAT_PDF, "Assembly top")
|
|
pctl.PlotLayer()
|
|
|
|
# And a gerber with only the component outlines (really!)
|
|
popt.SetPlotReference(False)
|
|
popt.SetPlotValue(False)
|
|
popt.SetPlotInvisibleText(False)
|
|
pctl.SetLayer(F_SilkS)
|
|
pctl.OpenPlotfile("AssyOutlinesTop", PLOT_FORMAT_PDF, "Assembly outline top")
|
|
pctl.PlotLayer()
|
|
|
|
# The same could be done for the bottom side, if there were components
|
|
popt.SetUseAuxOrigin(False)
|
|
|
|
# For documentation we also want a general layout PDF
|
|
# I usually use a shell script to merge the ps files and then distill the result
|
|
# Now I can do it with a control file. As a bonus I can have references in a
|
|
# different colour, too.
|
|
|
|
popt.SetPlotReference(True)
|
|
popt.SetPlotValue(True)
|
|
popt.SetPlotInvisibleText(False)
|
|
|
|
# Comments in, uhmm... green
|
|
#Note: currently, color is overidden by plot functions, so SetColor is not useful.
|
|
popt.SetColor( COLOR4D( 1.0, 0, 0, 1.0 ) ) # color = RED, GREEN, BLUE, OPACITY )
|
|
pctl.SetLayer(Cmts_User)
|
|
pctl.PlotLayer()
|
|
|
|
|
|
# At the end you have to close the last plot, otherwise you don't know when
|
|
# the object will be recycled!
|
|
pctl.ClosePlot()
|
|
|
|
# We have just generated your plotfiles with a single script
|