kicad/pcbnew/dialogs/panel_setup_rules_help.md

Top-level Clauses

(version <number>)

(rule <rule_name> <rule_clause> ...)

Rule Clauses

(constraint <constraint_type> ...)

(condition "<expression>")

(layer "<layer_name>")

Constraint Types

• annular_width
• clearance
• courtyard_clearance
• diff_pair_gap
• diff_pair_uncoupled
• disallow
• edge_clearance
• length
• hole
• hole_clearance
• silk_clearance
• skew
• track_width
• via_count

Item Types

• buried_via
• graphic
• hole
• micro_via
• pad
• text
• track
• via
• zone

Examples

(rule HV
   (constraint clearance (min 1.5mm))
   (condition "A.NetClass == 'HV'"))


(rule HV
   (layer outer)
   (constraint clearance (min 1.5mm))
   (condition "A.NetClass == 'HV'"))


(rule HV_HV
   # wider clearance between HV tracks
   (constraint clearance (min "1.5mm + 2.0mm"))
   (condition "A.NetClass == 'HV' && B.NetClass == 'HV'"))


(rule HV_unshielded
   (constraint clearance (min 2mm))
   (condition "A.NetClass == 'HV' && !A.insideArea('Shield*')"))

Notes

Version clause must be the first clause.

Rules should be ordered by specificity. Later rules take precedence over earlier rules; once a matching rule is found no further rules will be checked.

Use Ctrl+/ to comment or uncomment line(s).

Expression functions

All function parameters support simple wildcards (* and ?).

A.insideCourtyard('<footprint_refdes>')

True if any part of A lies within the given footprint's courtyard.

A.insideArea('<zone_name>')

True if any part of A lies within the given zone's outline.

A.isPlated()

True if A has a hole which is plated.

A.memberOf('<group_name>')

True if A is a member of the given group. Includes nested membership.

A.existsOnLayer('<layer_name>')

True if A exists on the given layer. The layer name can be either the name assigned in Board Setup > Board Editor Layers or the canonical name (ie: F.Cu).

NB: this returns true if A is on the given layer, independently of whether or not the rule is being evaluated for that layer. For the latter use a (layer "layer_name") clause in the rule.

More Examples

(rule "copper keepout"
   (constraint disallow track via zone)
   (condition "A.insideArea('zone3')"))


(rule "BGA neckdown"
   (constraint track_width (min 0.2mm) (opt 0.25mm))
   (constraint clearance (min 0.05mm) (opt 0.08mm))
   (condition "A.insideCourtyard('U3')"))


# prevent silk over tented vias
(rule silk_over_via
   (constraint silk_clearance (min 0.2mm))
   (condition "A.Type == '*Text' && B.Type == 'Via'"))


(rule "Distance between Vias of Different Nets"  
    (constraint hole_to_hole (min 0.254mm))
    (condition "A.Type =='Via' && B.Type =='Via' && A.Net != B.Net"))

(rule "Clearance between Pads of Different Nets"  
    (constraint clearance (min 3.0mm))
    (condition "A.Type =='Pad' && B.Type =='Pad' && A.Net != B.Net"))


(rule "Via Hole to Track Clearance"  
    (constraint hole_clearance (min 0.254mm))
    (condition "A.Type =='Via' && B.Type =='Track'"))

(rule "Pad to Track Clearance"  
    (constraint clearance (min 0.2mm))
    (condition "A.Type =='Pad' && B.Type =='Track'"))


(rule "clearance-to-1mm-cutout"
    (constraint clearance (min 0.8mm))
    (condition "A.Layer=='Edge.Cuts' && A.Thickness == 1.0mm"))


(rule "Max Drill Hole Size Mechanical"  
    (constraint hole (max 6.3mm))
    (condition "A.Pad_Type == 'NPTH, mechanical'"))

(rule "Max Drill Hole Size PTH"  
    (constraint hole (max 6.35mm))
    (condition "A.Pad_Type == 'Through-hole'"))